Pro/Piping Hands-on Workshop Tutorial
Pro/Engineer Wildfire 2.0




 


Introduction


Welcome to the introductory world of Pro/Piping.  Today the design and manufacturing of pipe systems is a manual process that requires prototye builds before the designer can effectively design the piping system.  Not only is this a costly solution, but it is time-consuming and prone to error.  Pro/Engineer Piping Design offers a solution that can be applied to design the piping systems within the electronic CAD model and develop the associative documentation. This tutorial will show three different methods to route piping so that all piping systems either large or small can determine how to use the tool to meet their requirements.

Objectives


During this tutorial you will learn:

Before you get started


This tutorial is intended to be used alongside Pro/ENGINEER Wildfire 2.0 M160.

Please make sure that Pro/ENGINEER Wildfire 2.0 is installed on your machine before continuing. Your hosting Hands-on Workshop Application Engineer will have this set up for you.  If not, please refer to the READ ME FIRST document.


It is recommended that you maximize the amount of working area on your screen by setting your monitor to the highest resolution setting, for example 1600x1200.

If you wish, you can resize your browser window's width using this page as a reference.  Size it until there is no horizontal scroll bar.  All pages in this tutorial are no wider this this one.

Use the Commands at the top of the page to step Forward, step Backwards or Home to return to the beginning of the tutorial. If the page contains more information than the visible screen, a scroll bar will appear along the vertical side. Scroll through the entire contents before progressing to the next step.

Finally, images are included with this tutorial to aid you.  If you see the enlargement icon ,  this offers the opportunity to enlarge the image in a separate window.
As an alternative to having this open along-side Pro/Engineer, you can also view a printable version by clicking here.

Piping Basic


Pro/Piping enables you to create 3-D piping designs as part of an integrated product development process.  Pro/Piping is used for parametrically creating and routing solid pipe parts in Pro/Engineer assemblies to and from assembly equipment.  Piping designs can either be specification driven or non-specification driven.

Specification driven designs involve using piping specifications and automated modelling tasks;this method is practiced by the Plant, Shipbuilding, and Aerospace industries.  Non-specification driven piping involves creating piping systems using manual tasks, and is often used when designing simple or flexible piping systems. 

In addition, 2-D schematic driven design information from Routed System Designer in the form of Process & Instrumentation diagram (P&ID) can be used ot pass design information into 3-D piping designs in Pro/ENGINEER. 

Below are four different exercises you can complete to increase you skills and understanding of Pro/Piping.  Depending on the piping design size and application, you will chose one or a combination of methods to apply Pro/Piping

Exercise 1: Routing Mechanical Piping Lines

Exercise 2: Routing Specification Driven Pipe Lines

Exercise 3: Routing Schematic Driven Pipe Lines

Exercise 4: Piping Documentation

Exercise 1: Manual Pipe routing

Objectives

After successfully completing this exercise, you will know how to :

Scenario

You are working on a new piping system for a compression unit; this involves the design of piping systems to recirculate cooling water to the compressor.  In this exercise, you will manually route a pipeline from Reservoir_F to Tank_B. You will be using manual piping techniques ,and also inserting several fitting types.

  • Download the files here
  • Unzip the file to the C:\

    Task 1. Open the Compression_top_level.ASM. 

    1. Start Pro/ENGINEER Wildfire 2.0 if necessary.
      If Pro/ENGINEER is already running ensure all windows are closed, and all items from the previous exercise are erased from memory.
    2. In the Folder Browser , browse to the following folder: c:\users\piping_wf2_tutorial.
    3.  Right-click on the Exercise1 folder and select Set Working Directory.
    4. Select the COMPRESSION_TOP_LEVEL.ASM from the browser to preview the model. Click Open File in Pro/E .
    5. Click Saved View List   from the main toolbar, and select Manual_pipe.

      If necessary, click Coordinate Systems  from the main toolbar to enable their display.
      If necessary, click Datum Planes  , Datum Axes  , Datum Points  from the main toolbar to disable their display.

      Compression_top_level.ASM

    6. Click Tools > Options and click Open a Configuration File
    7. Click Up One Level  and select config.pro file
    8. Click Open and OK to load the piping configurations.

     

  •  

    Task 2. Create a Subassembly for the pipeline leg. 

    1. Click Create Component  from the feature toolbar.
    2. Select Sub-Assembly as the Type.
    3. Type Leg-1 and click OK.


    4. Click Copy From Existing and then click Browse.
    5. Click Up One Level  and then double-click on the piping_specs folder.
    6. Select start and click Open.
    7. Click pipeline_start and click OK.
    8. Click Default Location  and then click OK


    Task 3. Create the required line stock (raw material parameter file) for the Leg-1 assembly 

    1. Click Applications > Piping from the main menu.
    2. Click Active Asm from the menu manager.
    3. Select the LEG-1.ASM from the model tree.

     

    The active assembly is where all Piping features will be created. It is best practice to use a dedicated piping assembly, and not the top-level assembly.

    1. Click Setup > Linestock > Create from the menu manager. 
    2. Type PIPE_150A as the name.
    3. Configure the Line Stock dialog box as shown in the following figure. 


      PIPE_150A Line Stock

     

    For shape type and corner type the check boxes configure selectable options, the green ball selection configures the default selection.

    1. Click Save   from the Line Stock dialog box.
    2. Double-click the exercise1 folder.
    3. Click the check mark , and then click Done/Return > Done/Return from the menu manager.
    4. Click Set Up > Line Stock > Read.
    5. If necessary Click Working Directory then Click Up One Level > Double-click on the piping_specs\linestocks folder.
      Click and drag to highlight all five Line Stock files as shown in the following figure.



      Line Stock Files Highlighted
       
    6. Click Open, and then click Done/Return > Done/Return from the menu manager. 
    7. Expand the LEG-1.ASM in the model tree.
    8. Notice the Line Stock features. 

     

    Task 4. Create a 150A pipeline between flanges on RESERVOIR_F to TANK_B.

    1. Select the Saved View icon and select the Manual_Pipe view.
    2. Click Pipeline > Create/Route from the menu manager.
    3. Type LEG-1 at the prompt.
    4. Click PIPE_150A from the menu manager.

     

    You should use a meaningful naming convention when creating pipelines. Enable and disable the display of datum features as required, no specific instructions will be given in this exercise.


    1. Turn on coordinate systems
    2. Click Set Start from the menu manager.
    3. Select PORT0 from FLANGE_SLIP_RF-STEEL on sub asm RESERVOIR_F as shown in the following figure.

    1. Click Extend from the menu manager.
    2. Click Csys Axis as the Type.
    3. Select the arrow on the Z-axis and hold left mouse button and drag the pipeline in the positive Z direction to approximately 900.  
    4. Change the extend option from Length to Offset Fm Ref
    5. Select Port0 from FLANGE_NECK_RF-STEEL-20K-100 on sub asm TANK_B as shown in the following figure.


                        
    6. Type 0 as the projection value.
    7. Click Complete Extend .
    8. Select TO PNT/PORT.
    9. Select Port0 from FLANGE_NECK_RF-STEEL-20K-100 on sub asm TANK_B > Done Return



      Pipeline Created

    Your pipeline is now routed, but you need to change the corner type to accept a fitting and you need to add the gaskets, flanges, reducer, and elbow.

    Task 5. We will now modify the corner so that we can insert a fitting

    1. Select MODIFY PIPE
    2. Check the CORNER TYPE  box
    3. Select on corner of pipeline.


    4. Click OK.
    5. Change value in new type box to FITTING.


    6. Select check mark .



      Modified Corner Style

    Task 6. Inserting an Elbow on the corner of the routed pipeline

    1. Click Fitting > Insert > Corner.
    2. Click Working Directory .
    3. Click Up One Level and then double-click on the piping_specs\fittinglib\elbow folder
    4. Select the ELBOW_90_BW part and click Open.
    5. Select the ELBOW_90_BW-STEEL-L-150 instance and click Open.
    6. Select the pipe end as shown in the following figure.

                                     
                   Selecting Pipe End                                                                                          Fitting Inserted
    7. Click Done from the menu manager.





       

       




       

    Task 7. Place a flange fitting on the start of the routed pipeline.


    1. Click Fitting > Insert > End.
    2. Click Up One Level  and then double-click on the flange folder 
    3. Select the FLANGE_NECK_RF part and click Open.
    4. Select the FLANGE_NECK_RF-STEEL-20K-150 instance and click Open.
    5. Select the pipe end as shown in the following figure.



      Selecting Pipe End


       

      Remember that the ‘existing’ flange is really just copied references from the end flange of a mating piping system.  Its geometry is shown for visualization and training purposes.


    6. Select PORT1 from the fitting in the sub-window.
    7. Click Datum Points  from the main toolbar to enable their display.
    8. Rotate the fitting in the sub-window slightly to view the datum point.
    9. Select datum point END.
    10. Click Done from the menu manager.

       

      1. Before clicking Done, you can use the Point and Orientation options to change the placement point on the fitting or the ‘clocking’ angle of the fitting on the pipeline.



      Fitting Inserted

    11. Click Fitting > Insert > End.
    12. Select the FLANGE_NECK_RF part from piping_specs/flange and click Open.
    13. Select the FLANGE_NECK_RF-STEEL-20K-100 instance and click Open.
    14. Select the pipe end as shown in the following figure.


       

    Selecting Pipe End

    1. Select PORT1 from the fitting in the sub-window.
    2. Click Datum Points   from the main toolbar to enable their display.
    3. Rotate the fitting in the sub-window slightly to view the datum point.
    4. Select datum point END.
    5. Click Done from the menu manager.


       

    Task 8. Place a reducer fitting on the routed pipeline. 


    1. Click Insert > Straightbk from the Fitting menu.
    2. Click Up One Level  and then double-click on the reducers folder 
    3. Select the RED_CONCENTRIC_BW part and click Open.
    4. Select the RED_CON_BW-STEEL-150X100 instance and click Open.
    5. Select the pipe segment as shown in the following figure.



      Selecting Pipe End

    6. Click Actual Len and enter 500.
    7. Select datum point PNT0 from the fitting in the sub-window.
    8. Select check mark  .
    9. Click Done > Done/Return from the menu manager.

       

      Notice that the selected port (PORT_0 or PORT_1) determines the orientation of the fitting on the pipeline. The system orients the Z axis of the selected Csys to the existing pipeline.




       

      Fitting Inserted
       


    Task 9. Modify the pipe linestock 


    1. Select MODIFY PIPE.
    2. Check the LINESTOCK box
    3. Select pipeline as shown in the figure.


    4. Click Done Sel.
    5. Change value in new type box to PIPE_100A.
    6. Select check mark

    Task 10. Review the features created in the model tree. 

    1. Expand the LEG-1.ASM in the model tree if necessary.
      Notice the pipeline features created. 

       
    2. Ensure the LEG-1.ASM is still the active assembly, as indicated by the green star symbol.



       Model Tree
       

       

      You can quickly set the active assembly by clicking Active Asm in the menu manager, and then selecting an assembly from the model tree.


    Task 11. Create a solid part from the Leg-1 pipeline. 


    1. Click Fabrication from the menu manager.
    2. Click Pipe Solid.
    3. Click View > Expand All  from the Pipe Solid dialog box.
    4. Click Select All .
    5. Click Open , and then click Working Directory
    6. Click Up One Level  once.
    7. Double-click on the piping_specs.
    8. Select the start and click Open.
    9. Select pipe_solid_start.prt as the Copy From option and click Apply .
    10. Click Make from the Pipe Solid dialog box, then click Close.




      Pipe Solid Created

    11. View the created pipe features and the solid LEG-1001, LEG-1002, and LEG-1003 part in the model tree.
    12. Select the LEG-1001.PRT from the model tree.
    13. Right-click and select Open.



        


       LEG-1001.PRT
    14. Click File > Save >Close Window from the main menu to return to the assembly.

    Summary


    After completing this module, you should now be able to:

     

     

     

    Congratulations! 

    You have completed the Pro/Piping Hands-On Tutorial For Manual Piping

     

    Click here to proceed to another exercise

     

     

    PTC offers a deeper dive training course that will provide a stronger understanding surrounding the Pro/Piping:

    Modeling 3-D Piping Designs with Pro/ENGINEER Wildfire 2.0

    If you are interested in attending, please visit the website at www.ptc.com

     

     

     

     

    Created by: Cassandra DeLeon Kemp